Free Trials

Download a free trial to find out which Altium software best suits your needs

Altium Online Store

Buy any Altium Products with few clicks or send us your quote to contact our sales


Download the latest in PCB design and EDA software

  • Altium Designer

    Complete Environment for Schematic + Layout

  • CircuitStudio

    Entry Level, Professional PCB Design Tool

  • CircuitMaker

    Community Based PCB Design Tool


    Agile PCB Design For Teams

  • Altium 365

    Connecting PCB Design to the Manufacturing Floor

  • Altium Concord Pro

    Complete Solution for Library Management

  • Octopart

    Extensive, Easy-to-Use Component Database

  • PDN Analyzer

    Natural and Effortless Power Distribution Network Analysis

  • See All Extensions

    World-Renowned Technology for Embedded Systems Development

  • Live Courses

    Learn best practices with instructional training available worldwide

  • On-Demand Courses

    Gain comprehensive knowledge without leaving your home or office

  • Altium 365 Viewer

    View & Share electronic designs in your browser

  • Altium Designer 20

    The most powerful, modern and easy-to-use PCB design tool for professional use


    Annual PCB Design Summit

    • Forum

      Where Altium users and enthusiasts can interact with each other

    • Blog

      Our blog about things that interest us and hopefully you too

    • Ideas

      Submit ideas and vote for new features you want in Altium tools

    • Bug Crunch

      Help make the software better by submitting bugs and voting on what's important

    • Wall

      A stream of events on AltiumLive you follow by participating in or subscribing to

    • Beta Program

      Information about participating in our Beta program and getting early access to Altium tools

    All Resources

    Explore the latest content from blog posts to social media and technical white papers gathered together for your convenience

    Altium Online Store

    Buy any Altium Products with few clicks or send us your quote to contact our sales


    Take a look at what download options are available to best suit your needs

    • Documentation

      The documentation area is where you can find extensive, versioned information about our software online, for free.

    • Training & Events

      View the schedule and register for training events all around the world and online

    • Design Content

      Browse our vast library of free design content including components, templates and reference designs

    • Webinars

      Attend a live webinar online or get instant access to our on demand series of webinars

    • Support

      Get your questions answered with our variety of direct support and self-service options

    • Technical Papers

      Stay up to date with the latest technology and industry trends with our complete collection of technical white papers.

    • Video Library

      Quick and to-the-point video tutorials to get you started with Altium Designer

    It’s Your Loss: Determining And Controlling Loss In The PCB Design Process

    Kella Knack
    |  July 23, 2019

    When it comes to designing a high-speed PCB, we always have to factor in the dynamic of signal loss. And, there are lots of areas where loss can occur. Accounting for all of these aspects of loss can be a challenging and time-consuming task as too much loss can prevent a high-speed PCB from functioning properly. This article will address the various aspects of loss, how they factor into the PCB design process, and how loss can be effectively determined and controlled.

    A Lot of Information and a Little Bit of History

    To begin, loss comes from three places:

    • Loss in the resin

    • Loss in the glass of the cloth

    • Loss in the copper

    Laminate or Dielectric Loss

    Just to review, loss is a function of both frequency and the length of the transmission line. When it comes to high-speed PCB design the thing to remember is the lower the loss the better, and loss changes with frequency. The higher the frequency, the more loss there is in any given material. The reason that loss exists and gets larger with frequency is that the changing electromagnetic field (RF field) causes the molecules in the dielectric to vibrate. The faster they vibrate, the more loss there is.

    Loss really comes into focus with the resin system or the laminate which is a composite of the resin and the glass. Note: the term laminate loss is used interchangeably with dielectric loss.

    Part of the laminate selection process focuses on the loss tangent tan(f) or dissipation factor (DF) of any given material. The tan(f) is a measure of how much of the energy in an RF signal is lost in the dielectric of the PCB and it is one of the properties of a piece of laminate that is provided by the laminate supplier.

    Different Styles of Glasses

    Historically, manipulating the loss in laminates involved two things—modifying the glass or modifying the resin. Nearly all glass used to make the cloths for PCBs is E (electrical) glass. It is formulated for easy weaving and adhesion of the resin to the glass.

    The challenge is that E glass has a relatively high loss tangent. Some years back, a couple of glass manufacturers modified the glass formula to create S (strength) glass which has a lower loss than E glass. Early on, almost anyone going up the speed curve chose a laminate made with S glass. The problem was that there was only one source for S glass (Nitobo) and it was located in Japan. Additionally, there was only one widely available laminate, Nelco’s original 4000-13 SI, that contained S glass. Overnight the entire industry changed when the earthquake and tsunami hit Japan in 2011 and S glass went entirely away. 

    All of the other laminate suppliers modified their resin systems such that their laminates became low loss so the need for S glass disappeared and it is rarely used. The real benefit of this is that the sole-source problem that was associated with S glass has gone away.

    Copper Loss and Skin-effect loss

    Once the resin systems had been successfully addressed, the industry next turned to looking at loss in copper.

    Copper loss has three components:

    • The wider the trace, the more surface area there is.

    • The roughness of the copper

    • The basic conductivity of the copper

    In contrast to dielectric loss, copper or skin-effect loss is associated with the current that flows into conductors and crowds into a thin layer near the surface at high frequencies. Similar to dielectric loss, skin-effect loss gets larger as frequencies go up. It is compensated for by increasing the width of the traces to create more surface area. A wider trace means lower skin-effect loss. In designing a PCB stackup, tradeoffs between skin-effect losses and dielectric losses are made by determining which dielectric/laminate to use and how wide the traces on the PCB will be.

    Historically, copper was made rough so that it would bond to the laminate. The problem was that this rough copper produced quite a bit of loss. But, because loss was not an initial area of concern, the roughness of the copper was not an issue. Figures 1 and 2 show the difference between smooth and rough copper. Figure 1 is the smooth copper and Figure 2 is the rough copper.  

    Figure 1. Very Low Profile Copper Foil (VLP)

    Figure 2. Reverse Treat Copper Foil (RTF)

    To address the problem of loss and copper roughness, the industry pushed for very smooth or very low profile (VLP) copper. The problem was that it did not bond well. Eventually, a whole new set of chemistry was developed to make the smooth copper bond to the resins during lamination.

    However, no matter how much effort has been put into making the copper smooth, it still has irregularities—peaks and valleys—which contribute to loss. When the copper was being made rough to ensure that it would bond to the resin, the height of the roughness was 8 or 10 microns. The smooth copper is 2 microns, but it still contributes to loss. There has to be some way to model those 2 microns, and there are three different math models that enable that process.

    In terms of the conductivity of copper, all copper is plated so it is a constant across the industry and is not a variable relative to loss.

    Now, there are two loss elements left that the engineer needs to manipulate: how much surface there is (trace width), and how rough the surface is. There are two simulators of choice which are primarily used to model loss: Polar’s SI9000, and Mentor’s Hyperlynx with the GHz package. Note: The three accepted models for surface roughness are in the Polar tool. 

    The Good News and the Bad News

    Not so many years ago (in the overall span of the history of PCBs), it was difficult to get loss information from laminate companies. In 2011, the testing of materials was done such that the necessary loss information could become known. Nowadays, as a result of the pressure coming from the design community, all the suppliers of low-loss materials, including those offshore, provide good, reliable loss information for their materials.

    The Effect of Vias on Path Loss

    So, once we got all the material information in place, there came yet another loss design wrinkle that needed addressing. We all assumed that, because of loss, the nets that we needed to worry about were the long ones, but it turned out that it was actually the short ones that were failing. In 2010, IBM published a paper entitled, “Short May Not Be Better”, DesignCon 2010, Steinberger, et al. IBM had built a really big server that contained a lot of 10Gb or faster nets. The concern was that the failures would be the result of these long nets. Instead, the short nets failed because of the reflections off the vias. While both the long and short nets had vias, the long nets had enough loss that they absorbed the reflections from the vias.

    Figure 3 illustrates what occurred with the short nets, which failed. 

    Figure 3. Loss vs Frequency for two 8” (20 cm) Lines, Routed on Two Different Layers

    As shown, the red curve has a roll-off as would be expected. When the via went from the device lead to a trace near the bottom of the board and then back up to the lead, the capacitance was distributed along the length of the via. When the via only went down to layer three (the blue curve) and then crossed, the capacitance of the via was “hanging down” such that it caused disastrous loss. If you use a simulation tool and simulate that via, you create a band-pass filter. .3pf is not a big deal until you are at 4-5Ghz. Above that, it can be a huge problem.

    The key thing here is that the reflection of the via of the short net is not lost in a lossy line. Rather, If you have to route on a layer near the top of the board, you have to back drill the unwanted capacitance of the via. While doable, this is by no means a cheap proposition. Instead, we recommend the use of the following technique: Put all of the fast traces near the bottom (signal layers) of the board. Note: In a big backplane this approach won’t work. When you have a backplane with nothing but high-speed signals, you have no choice other than to back drill.


    The subject of loss is multifaceted and somewhat complicated. However, with today’s material information supplied by laminate manufacturers and the capabilities of current simulation toolsets, it is possible to predict loss with extreme precision. 

    Altium Designer® includes signal integrity tools for PCB Designers as well as power integrity analysis tools in a single program talk to an Altium expert today to learn more. 


    1. “High-Speed Signal Path Losses as Related to PCB Laminate Type and Copper Roughness,” Lee Ritchey, John Zasio, Rich Pangier, and Gerry Partida. DesignCon 2013 proceedings.

    2. “When Shorter Isn’t Better,” Michael Steinberger, Paul Wildes, Erick Brock, Walter Katz, and Mike Higgins. DesignCon 2010, Track 7, Multi-Gigabit Serial Interconnects, 7-TA3.

    3. Ritchey, Lee W. and Zasio, John J., “Right The First Time, A Practical Handbook on High-Speed PCB and System Design, Volumes 1 and 2.”

    About Author

    About Author

    Kella Knack is Vice President of Marketing for Speeding Edge, a company engaged in training, consulting and publishing on high speed design topics such as signal integrity analysis, PCB Design ad EMI control. Previously, she served as a marketing consultant for a broad spectrum of high-tech companies ranging from start-ups to multibillion dollar corporations. She also served as editor for various electronic trade publications covering the PCB, networking and EDA market sectors.

    most recent articles

    Back to Home