Free Trials

Download a free trial to find out which Altium software best suits your needs

How to Buy

Contact your local sales office to get started on improving your design environment


Download the latest in PCB design and EDA software

  • Altium Designer

    Complete Environment for Schematic + Layout

  • CircuitStudio

    Entry Level, Professional PCB Design Tool

  • CircuitMaker

    Community Based PCB Design Tool


    Agile PCB Design For Teams

  • Altium 365

    Connecting PCB Design to the Manufacturing Floor

  • Altium Concord Pro

    Complete Solution for Library Management

  • Octopart

    Extensive, Easy-to-Use Component Database

  • PDN Analyzer

    Natural and Effortless Power Distribution Network Analysis

  • See All Extensions

    World-Renowned Technology for Embedded Systems Development

  • Live Courses

    Learn best practices with instructional training available worldwide

  • On-Demand Courses

    Gain comprehensive knowledge without leaving your home or office

  • Altium 365 Viewer

    View & Share electronic designs in your browser

  • Altium Designer 20

    The most powerful, modern and easy-to-use PCB design tool for professional use


    Annual PCB Design Summit

    • Forum

      Where Altium users and enthusiasts can interact with each other

    • Blog

      Our blog about things that interest us and hopefully you too

    • Ideas

      Submit ideas and vote for new features you want in Altium tools

    • Bug Crunch

      Help make the software better by submitting bugs and voting on what's important

    • Wall

      A stream of events on AltiumLive you follow by participating in or subscribing to

    • Beta Program

      Information about participating in our Beta program and getting early access to Altium tools

    All Resources

    Explore the latest content from blog posts to social media and technical white papers gathered together for your convenience


    Take a look at what download options are available to best suit your needs

    How to Buy

    Contact your local sales office to get started improving your design environment

    • Documentation

      The documentation area is where you can find extensive, versioned information about our software online, for free.

    • Training & Events

      View the schedule and register for training events all around the world and online

    • Design Content

      Browse our vast library of free design content including components, templates and reference designs

    • Webinars

      Attend a live webinar online or get instant access to our on demand series of webinars

    • Support

      Get your questions answered with our variety of direct support and self-service options

    • Technical Papers

      Stay up to date with the latest technology and industry trends with our complete collection of technical white papers.

    • Video Library

      Quick and to-the-point video tutorials to get you started with Altium Designer

    Competition for HDI: VeCS

    Happy Holden
    |  March 4, 2019

    Not long ago, a very creative engineer in Europe proposed a novel concept for layer-to-layer connections that has higher density than the conventional through-hole. That engineer is Joan Torne’ of NEXTGin Technologies BV [1] and his technology is called, “Vertical Conductive Structures-VeCS”. It employs the conventional PCB TH fab equipment, increases densities to that of HDI, with capabilities down to 0.4 mm pitch BGAs.

    The concept is to peck-drill or route a slot or cavity into the board (for blind connections) or through the board, then metallize and plate. In the final fabrication step, slightly larger holes are drilled that creates a vertical connection between layers, as seen in Figure 1 a.  As you can see from the illustration in Figure 1b, these smaller vertical connections take up less room than a conventional drilled through-hole, thus allowing more space for routing. In the example I created in Figure 1c, I compared TH, microvias and VeCS for a 1.0 mm pitch BGA. For the TH, you can squeeze 2-tracks under the dog-bone breakouts, while using swing-microvias, you can achieve 7-tracks. Equally as dense is the VeCS breakouts with 7-tracks. When dropping to 0.5 mm pitch BGAs, for TH, there is no room to route more than one-track through, if using via-in-pad, but for HDI, you can route 7 tracks between the blind-vias. VeCS is almost as dense with the ability to route 5-tracks between the vertical connections. For the larger pitches, there is some flexibility with VeCS breakout, as seen in the 1.0 mm with two different routing into the cavity.

    FIGURE 1. a. The VeCS technology creates vertical traces to connect layers together rather than employing an entire hole; b. A 3D view  shows the advantage of additional routing space created by using only the vertical wall; c. A comparison of the two common technologies, TH and HDI versus VeCS for two BGA breakouts-1.0 mm and 0.5 mm BGAs.

    The routing rules for Figure 1c are shown in Table 1:

    TABLE 1. Design and routing rules for the two BGA breakouts and routings for through-hole, HDI-microvias and VeCS technology

    The VeCS manufacturing process hasn’t changed the conventional multilayer manufacturing process, just a few additional steps have been added:

    1. Drill or route a slot between BGA lands

    2. Metallize as normal

    3. Image with VeCS breakouts adjacent to the metallized slot

    4. Plate as normal

    5. Strip and etch as normal

    6. At final fabrication, drill out the metallization for vertical traces

    The process (seen in Figure 2) does not require the use of a laser drill and is compatible with a panel plate process.

    FIGURE 2. The VeCS fabrication process is very conventional

    The only article published on the technology, The PCB magazine-February 2017 [2], indicated Joan had created test vehicles to test reliability and used Altium Designer® to create the artwork. The fabrication and testing were done by WUS. After multiple lead-free reflow cycles and thermal cycling to failure-results were comparable with through-holes. Signal integrity appears to be slightly better as the vertical trace has less inductance than a hole, but the slots or cavities may interfere with ground pours.

    For the cost trade-offs, the increase routing density will hopefully allow fewer signal and reference layers or a smaller board with more-up per panel. Thus, saving money and paying for the one-up drilling or routing process to create the cavities or slots in the board.

    If this is a concept that you might use, contact your favorite PCB fabricator to try a test board. If you want to use it in a design, contact NEXTGin [1] to see about the patent status of the technology.  NEXTGin report two PCB fabricators are currently using the technology.


    2. Starkey, Pete, Interview of Joan Tourne’, “Vertical Conductive Structures–a New Dimension in High-Density Printed Circuit Interconnect”, The PCB magazine, February 2017, pp 16-20

    About Author

    About Author

    Happy Holden is retired from GENTEX Corporation (one of the U.S.'s largest automotive electronics OEM. He was the Chief Technical Officer for the world’s biggest PCB Fabricator-HonHai Precision Industries (Foxconn) in China. Prior to Foxconn, Mr. Holden was the Senior PCB Technologist for Mentor Graphics; he was the Advanced Technology Manager at NanYa/Westwood Associates and Merix Corporations. He retired from Hewlett-Packard after over 28 years. His prior assignments had been as director of PCB R&D and Manufacturing Engineering Manager. While at HP, he managed PCB design, PCB partnerships, and automation software in Taiwan and Hong Kong. Happy has been involved in advanced PCB technologies for over 47 years. He has published chapters on HDI technology in 4 books, as well as his own book, the HDI Handbook, available as a free e-Book at and de recently completed the 7th Edition of McGraw-Hill's PC Handbook with Clyde Coombs.

    most recent articles

    Back to Home